modeling-app/public/kcl-samples/curtain-wall-anchor-plate/main.kcl

// Curtain Wall Anchor Plate
// A structural steel L-plate used to anchor curtain wall systems to concrete slabs, with elongated holes for adjustability and bolts with nuts and base plates for secure fastening

// Set units in millimeters (mm)
@settings(defaultLengthUnit = mm, kclVersion = 1.0)

// Define parameters
slabPlateBaseLength = 300
slabPlateHookLength = 80
slabPlateWidth = 200
slabPlateThickness = 8
offsetSlabRail = 200

// Generate L-shaped anchor profile with base and hook flange
// Includes fillets at internal and external corners for strength and safety
fn lProfileFn(lengthBase, lengthHook, width, thickness) {
  profilePlane = startSketchOn(offsetPlane(XZ, offset = -width / 2))
  profileShape = startProfile(profilePlane, at = [0, 0])
    |> yLine(length = lengthHook, tag = $hookOutside)
    |> xLine(length = thickness)
    |> yLine(length = thickness - lengthHook, tag = $hookInside)
    |> xLine(length = lengthBase - thickness, tag = $baseInside)
    |> yLine(length = -thickness)
    |> line(endAbsolute = [profileStartX(%), profileStartY(%)], tag = $baseOutside)
    |> close()
  profileBody = extrude(profileShape, length = width)
    |> fillet(
         radius = thickness,
         tags = [
           getCommonEdge(faces = [baseInside, hookInside])
         ],
       )
    |> fillet(
         radius = thickness * 2,
         tags = [
           getCommonEdge(faces = [baseOutside, hookOutside])
         ],
       )
  return profileBody
}

// Create a hexagonal shape used for bolt and nut heads
fn hexagonFn(plane, radius) {
  shape = startProfile(plane, at = [-radius, 0])
    |> angledLine(angle = 60, length = radius)
    |> xLine(length = radius)
    |> angledLine(angle = -60, length = radius)
    |> angledLine(angle = -120, length = radius)
    |> xLine(length = -radius)
    |> line(endAbsolute = [profileStartX(%), profileStartY(%)])
    |> close()
  return shape
}

// Build a bolt with a hexagonal head and cylindrical shaft
fn boltFn(diameter, length) {
  boltHeadPlane = startSketchOn(XY)
  boltHeadShape = hexagonFn(plane = boltHeadPlane, radius = diameter)
  boltHeadBody = extrude(boltHeadShape, length = diameter * 0.7)
  boltPlane = startSketchOn(boltHeadBody, face = START)
  boltShape = circle(boltPlane, center = [0, 0], radius = diameter / 2)
  boltBody = extrude(boltShape, length = length)
  return boltBody
}

// Construct a bolt assembly with base plate and hex nut
// Assembles all parts for realistic anchor simulation
fn boltWithPlateAndNutFn(diameter, length, gap) {
  plateSide = diameter * 3
  plateplane = startSketchOn(offsetPlane(XY, offset = -gap))
  plateShape = startProfile(plateplane, at = [-plateSide / 2, -plateSide / 2])
    |> yLine(length = plateSide)
    |> xLine(length = plateSide)
    |> yLine(length = -plateSide)
    |> line(endAbsolute = [profileStartX(%), profileStartY(%)])
    |> close()
  plateBody = extrude(plateShape, length = -diameter * 0.3)
  nutPlane = startSketchOn(plateBody, face = START)
  boltHeadShape = hexagonFn(plane = nutPlane, radius = 12)
  boltHeadBody = extrude(boltHeadShape, length = diameter * 0.7)
  boltBody = boltFn(diameter = diameter, length = gap + diameter + 3)
  mergedBody = union([boltHeadBody, boltBody])
  return mergedBody
}

// Generate the plate geometry with a vertical hook for slab attachment
slabPlate = lProfileFn(
  lengthBase = slabPlateBaseLength,
  lengthHook = slabPlateHookLength,
  width = slabPlateWidth,
  thickness = slabPlateThickness,
)

// Define oblong holes for bolts, allowing positional adjustment
wideHoleWidth = 12
wideHoleLength = 60
wideHoleOffset = 30

// Two slots mirrored across the plate width
wideHolePlane = startSketchOn(XY)
wideHoleShape = startProfile(
       wideHolePlane,
       at = [
         -(wideHoleLength - wideHoleWidth) / 2,
         wideHoleWidth / 2
       ],
     )
  |> xLine(length = wideHoleLength - wideHoleWidth)
  |> tangentialArc(endAbsolute = [
       (wideHoleLength - wideHoleWidth) / 2,
       -wideHoleWidth / 2
     ])
  |> xLine(length = wideHoleWidth - wideHoleLength)
  |> tangentialArc(endAbsolute = [profileStartX(%), profileStartY(%)])
  |> close()
  |> translate(
       %,
       x = offsetSlabRail,
       y = wideHoleOffset - (slabPlateWidth / 2),
       z = -1,
     )
wideHoleVoidLeft = extrude(wideHoleShape, length = slabPlateThickness + 2)
wideHoleVoidRight = clone(wideHoleVoidLeft)
  |> translate(
       %,
       x = 0,
       y = slabPlateWidth - (wideHoleOffset * 2),
       z = 0,
     )

// Cut the holes into the anchor plate body
slabPlatePunchOne = subtract([slabPlate], tools = [wideHoleVoidLeft])
slabPlatePunchTwo = subtract([slabPlatePunchOne], tools = [wideHoleVoidRight])

// Add two bolt assemblies into the oblong slots
// Properly rotated and spaced to match anchor hole layout
slabPlateBolts = boltWithPlateAndNutFn(diameter = 10, length = 20, gap = slabPlateThickness + 5)
  |> rotate(
       %,
       roll = 180,
       pitch = 0,
       yaw = 0,
     )
  |> translate(
       %,
       x = offsetSlabRail,
       y = wideHoleOffset - (slabPlateWidth / 2),
       z = 5,
     )
  |> patternLinear3d(
       %,
       instances = 2,
       distance = slabPlateWidth - (wideHoleOffset * 2),
       axis = [0, -1, 0],
     )