modeling-app/docs/kcl-std/functions/std-sketch-revolve.md

title, excerpt, layout

title	excerpt	layout
std::sketch::revolve	Rotate a sketch around some provided axis, creating a solid from its extent.	manual

Rotate a sketch around some provided axis, creating a solid from its extent.

This, like extrude, is able to create a 3-dimensional solid from a 2-dimensional sketch. However, unlike extrude, this creates a solid by using the extent of the sketch as its revolved around an axis rather than using the extent of the sketch linearly translated through a third dimension.

Revolve occurs around a local sketch axis rather than a global axis.

You can provide more than one sketch to revolve, and they will all be revolved around the same axis.

revolve(
  @sketches: [Sketch; 1+],
  axis: Axis2d | Edge,
  angle?: number(Angle),
  tolerance?: number(Length),
  symmetric?: bool,
  bidirectionalAngle?: number(Angle),
  tagStart?: tag,
  tagEnd?: tag,
): Solid

Arguments

Name	Type	Description	Required
sketches	[Sketch; 1+]	The sketch or set of sketches that should be revolved	Yes
axis	Axis2d or Edge	Axis of revolution.	Yes
angle	number(Angle)	Angle to revolve (in degrees). Default is 360.	No
tolerance	number(Length)	Tolerance for the revolve operation.	No
symmetric	bool	If true, the extrusion will happen symmetrically around the sketch. Otherwise, the extrusion will happen on only one side of the sketch.	No
bidirectionalAngle	number(Angle)	If specified, will also revolve in the opposite direction to 'angle' to the specified angle. If 'symmetric' is true, this value is ignored.	No
tagStart	tag	A named tag for the face at the start of the revolve, i.e. the original sketch.	No
tagEnd	tag	A named tag for the face at the end of the revolve.	No

Returns

Solid - A solid is a collection of extrude surfaces.

Examples

part001 = startSketchOn(XY)
    |> startProfile(at = [4, 12])
    |> line(end = [2, 0])
    |> line(end = [0, -6])
    |> line(end = [4, -6])
    |> line(end = [0, -6])
    |> line(end = [-3.75, -4.5])
    |> line(end = [0, -5.5])
    |> line(end = [-2, 0])
    |> close()
    |> revolve(axis = Y) // default angle is 360

// A donut shape.
sketch001 = startSketchOn(XY)
    |> circle( center = [15, 0], radius = 5 )
    |> revolve(
        angle = 360,
        axis = Y,
    )

part001 = startSketchOn(XY)
    |> startProfile(at = [4, 12])
    |> line(end = [2, 0])
    |> line(end = [0, -6])
    |> line(end = [4, -6])
    |> line(end = [0, -6])
    |> line(end = [-3.75, -4.5])
    |> line(end = [0, -5.5])
    |> line(end = [-2, 0])
    |> close()
    |> revolve(axis = Y, angle = 180)

part001 = startSketchOn(XY)
    |> startProfile(at = [4, 12])
    |> line(end = [2, 0])
    |> line(end = [0, -6])
    |> line(end = [4, -6])
    |> line(end = [0, -6])
    |> line(end = [-3.75, -4.5])
    |> line(end = [0, -5.5])
    |> line(end = [-2, 0])
    |> close()
    |> revolve(axis = Y, angle = 180)

part002 = startSketchOn(part001, face = END)
    |> startProfile(at = [4.5, -5])
    |> line(end = [0, 5])
    |> line(end = [5, 0])
    |> line(end = [0, -5])
    |> close()
    |> extrude(length = 5)

box = startSketchOn(XY)
    |> startProfile(at = [0, 0])
    |> line(end = [0, 20])
    |> line(end = [20, 0])
    |> line(end = [0, -20])
    |> close()
    |> extrude(length = 20)

sketch001 = startSketchOn(box, face = END)
    |> circle( center = [10,10], radius = 4 )
    |> revolve(
        angle = -90,
        axis = Y
    )

box = startSketchOn(XY)
    |> startProfile(at = [0, 0])
    |> line(end = [0, 20])
    |> line(end = [20, 0])
    |> line(end = [0, -20], tag = $revolveAxis)
    |> close()
    |> extrude(length = 20)

sketch001 = startSketchOn(box, face = END)
    |> circle( center = [10,10], radius = 4 )
    |> revolve(
        angle = 90,
        axis = getOppositeEdge(revolveAxis)
    )

box = startSketchOn(XY)
    |> startProfile(at = [0, 0])
    |> line(end = [0, 20])
    |> line(end = [20, 0])
    |> line(end = [0, -20], tag = $revolveAxis)
    |> close()
    |> extrude(length = 20)

sketch001 = startSketchOn(box, face = END)
    |> circle( center = [10,10], radius = 4 )
    |> revolve(
        angle = 90,
        axis = getOppositeEdge(revolveAxis),
        tolerance = 0.0001
    )

sketch001 = startSketchOn(XY)
  |> startProfile(at = [10, 0])
  |> line(end = [5, -5])
  |> line(end = [5, 5])
  |> line(endAbsolute = [profileStartX(%), profileStartY(%)])
  |> close()

part001 = revolve(
   sketch001,
   axis = {
     direction = [0.0, 1.0],
     origin = [0.0, 0.0]
  }
)

// Revolve two sketches around the same axis.

sketch001 = startSketchOn(XY)
profile001 = startProfile(sketch001, at = [4, 8])
    |> xLine(length = 3)
    |> yLine(length = -3)
    |> xLine(length = -3)
    |> line(endAbsolute = [profileStartX(%), profileStartY(%)])
    |> close()

profile002 = startProfile(sketch001, at = [-5, 8])
    |> xLine(length = 3)
    |> yLine(length = -3)
    |> xLine(length = -3)
    |> line(endAbsolute = [profileStartX(%), profileStartY(%)])
    |> close()

revolve(
    [profile001, profile002],
    axis = X,
)

// Revolve around a path that has not been extruded.

profile001 = startSketchOn(XY)
    |> startProfile(at = [0, 0])
    |> line(end = [0, 20], tag = $revolveAxis)
    |> line(end = [20, 0])
    |> line(end = [0, -20])
    |> close(%)

sketch001 = startSketchOn(XY)
    |> circle(center = [-10, 10], radius = 4)
    |> revolve(angle = 90, axis = revolveAxis)

// Revolve around a path that has not been extruded or closed.

profile001 = startSketchOn(XY)
    |> startProfile(at = [0, 0])
    |> line(end = [0, 20], tag = $revolveAxis)
    |> line(end = [20, 0])

sketch001 = startSketchOn(XY)
    |> circle(center = [-10, 10], radius = 4)
    |> revolve(angle = 90, axis = revolveAxis)

// Symmetrically revolve around a path.

profile001 = startSketchOn(XY)
    |> startProfile(at = [0, 0])
    |> line(end = [0, 20], tag = $revolveAxis)
    |> line(end = [20, 0])

sketch001 = startSketchOn(XY)
    |> circle(center = [-10, 10], radius = 4)
    |> revolve(angle = 90, axis = revolveAxis, symmetric = true)

// Bidirectional revolve around a path.

profile001 = startSketchOn(XY)
    |> startProfile(at = [0, 0])
    |> line(end = [0, 20], tag = $revolveAxis)
    |> line(end = [20, 0])

sketch001 = startSketchOn(XY)
    |> circle(center = [-10, 10], radius = 4)
    |> revolve(angle = 90, axis = revolveAxis, bidirectionalAngle = 50)